You can watch the video or follow our step by step tutorial.
Step 1: Create a Project
Expand the Data panel in the Fusion 360 interface and click the New Project button to define the dedicated repository for all designs related to F1 in Schools.
Type in the name of the project, for example “F1 in Schools,” and press Enter. After a few seconds, the project will appear in the list.
Double click the project name to view the contents. By default, it shows all the data available within the project. For now it is empty.
Return to the main Fusion 360 window.
Step 2: Create a New Design and Sketch
In Fusion 360, click the File button in the upper-left and select New Design. Before you can save your design, you must start modelling in the work space.
Select Sketch > Rectangle > 2-Point Rectangle tool from the drop down menu to start sketching.
Click OK in the notification dialog if it appears. You may also choose not to display this notice in the future.
Select the right side plane to base the sketch on.
Move your cursor to the centre of the axis and click when it becomes highlighted to place the corner of the rectangle.
Move your cursor up and right to begin to draw a rectangle. In the boxes, type 50(mm) in the box for the vertical line, then press Return/Enter. Type 223(mm) in the horizontal, then press Return again to input the dimension. Finally press Return to finish.
Click Stop Sketch.
You can now use the Shift key and hold down the middle mouse button (2 fingers on Mac track pad) to rotate the view. Alternately, use the view cube to set the orientation you need. The house icon fits the model in the window.
You will now see that the shape you have created is two-dimensional. Now you need to make it solid/three-dimensional
From the Create dropdown menu, select Extrude. Select the sketch profile you have just made.
In the window, type 32.5(mm) for Distance, Select Symmetric for Direction, and check New Body is selected for Operation. Click OK.
This will create a block that has a plane running through the center of it. This will be useful later, when you need things to be the same on both sides of your car.
Save your design by clicking the Save icon on the upper left. Enter a name like “F1 in Schools Block” in the dialog box, and select which Autodesk 360 project you want to save your design to.
Step 3: Create Features in the Block
Now you are going to produce the hole in the end of the block that houses the CO2 cartridge during racing. Select Sketch > Circle > Center Diameter Circle.
You then need to select where to sketch the circle. There are different ways you cando this. Select the left plane by moving your cursor near it, extending the Origin tab inthe Browser window and selecting the YZ plane, or using the View Cube to select theleft side of the block. This will keep the back end of the car at the origin, which will beuseful later on.
Option A: Select the left plane by moving your cursor near it Option B: Extend the Origin tab in the Browser window and select the YZ plane Option C: Use the View Cube to select the left side of the block. This will keep the back end of the car at the origin, which will be useful later on.
Your block will then spin to allow you to work on it easier. On the right side of the window you should see the sketch palette. Make sure Options > Snap is selected. This makes it easier to position things on the grid.
Move your cursor up from the origin and you should see a dashed blue line. This indicates it is the center of that face. Go about half way up and click. Dimension the circle to 19mm diameter.
You now need to position the circle acutely from the bottom of the block. Select Sketch > Sketch Dimension from the Tool Bar. Now click the center of your circle and the bottom center of the block (origin point). Change this dimension to 29mm.
The circle should update to a new position. Stop the sketch.
Select Modify > Press Pull from the Tool Bar and select the circle.
In the Extrude window, type a distance of -52mm. By putting Minus (-) it should flick the preview arrow around and make a Cut inside the block. You can also do this by dragging the blue arrow, but this method isn’t as accurate. Make sure the Operation says Cut. Click OK.
You now need to model the Tether Line Slot. This is the slot that runs underneath the car. Select a Center Rectangle from the Sketch icon on the Tool Bar. Select the same face you were just working on. Start the center of the rectangle at the Origin. Make the sizes 6mm across and 12mm down.
Stop the sketch. Select Press Pull from the Tool Bar (or right click to see a shortcut menu). Select the top part of the rectangle to extrude.
You now need to cut this part all the way through the block. You could drag the blue arrow inside the block, or select Cut from the Operation option and Through All from Extent. Be sure to select Flip to cut inside the block or you may get an error message.
Rotate the model to check everything has worked.
You should now notice there is a timeline at the bottom of the screen. This is like a history of everything you have done so far. You can double click to edit these parts and your model will update with the changes.
Click the Save icon, name your part file, and Save.
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